Adding geometry to cut as a pocket with a finishing pass

One technique which is often suggested to avoid slotting is to add geometry around a part which one wishes to cut out and cut as a pocket down to tab depth — here’s one technique for that.

In this case, the project is a bevel gauge which will be cut out of 0.0625" (~1.5mm) thick aluminum:

bevelgauge

Due to the narrowness of the angles, an 0.03125" endmill has to be used, so after importing and scaling the file (we will be cutting out one which is 3") we select the perimeter and offset it twice, once by the desired chipload (0.01") and again by half again the endmill diameter:

(control click on the profile, then delete the extraneous bits of path left in the centers of the divots)

1 Like
Setting up roughing and finishing pass in CC
What CNC bit used to cut out letters
What Drill bits to use?
Inconsistent Tool Paths
First aluminum fail, figuring out why
Cutting Name Necklaces with Nomad on Brass (0.8mm thick)
Why the lines when cut
Why did this happen..?
3/4” Bowl Bit Issue
How to generate toolpath?
ShapeokoXXL: Backlash and bad circles issues
CarbideCreate/Nomad cut size slightly wrong
Uneven Depth of Cut issue
Uneven Depth of Cut issue
Z axis not retracting enough
So here's a new one to me
V bit moving away from the initial line
First cut too deep
Carbide create toolpath issue
WTF Carbide motion?!?!?!
Contour issue and wobbily straight lines
Burn marks/smoking while cutting
CM Toolpath Issue
Help with unexpected overcut (broken bit)
Error when cutting
Workpiece holding issue possibly?
Square Box not Square
Nomad 3 documentation and downloads
Baltic birch Plywood
Carbide create beginner
Problem with file
Carbide Compact Router
New software missing some features?
Carbide create missing materials in material drop down list
Calibration gremlins and odd .001mm -Y jog behavior
End Mill Advice
Over Cutting Corners in Y Axis
Compression cutter wandering!
Bit wandered help
Cutting Depth Issues (was What is the problem)
Recommened Tool Setting for uxcell 1 inch bit
Preventing collisions in Fusion 360
Shapeoko XXL - final pass is stretched or offset
Cutting off the end of a ruler sized stick
Bad scratch and terrible results
CC and Tiling issue
Switched to compression bits and getting inconsistent cuts
Brushless Makita Mod (unsupported)
Inaccurate cutttings
Speeds, feeds, plunge rates
Really bad cut, wrong bit? What happened?!
My project CRASHED today, went through my tabs!
Carbide motion will not cut tabs
Erm, where's this..?
Fuzzy cuts on birch plywood
Shapeoko XXL - Crash Sound
Help needed applying CCreate to an Aussie build Sharp CNC
Chips stuck in the cut
Extra unnecessary cuts
Help a newbie out
Looking to make a crib board!
Shapeoko XL Cutting Inconsistently
Second Toolpath is Offset -0.5" along X-Axis
Z Zero depth will not change
New Terms for a Newbie - "Adding Geometry"
Pocket operation leaves an indent
Job accident with weird movement
Cut jumping off track
What's going on here? #3
A picture is worth 1000 words
Adding New Tool to Carbide Create 514
Strange "star" appearing on my simulation & toolpath
Odd behaviour from my Shapeoko 3
First layer carved incorrectly + curves discontinuities
Shapeoko xxl cutting to much at once?
My Z-axis seems to be LOST!
First sign..need ideas and some questions answered
Having Issue with Cutting Flipped Fillet
3XXL 6061 Machining
Thoughts on this?
Cutting 1mm copper with SO3
How to smooth out entry and exit of tool path "nibs"?
Concave Contour?
First Cut - Weird Issue
Small groove where endmill plunges
201 Bit Broke - How should I adjust my settings
Odd issue with cut depth

Select the offset paths and assign a pocket operation:

Note the Depth Per Pass and set the depth of the pocket to leave the desired tab thickness, in this case, twice the 0.098mm depth per pass.

Select the original path and assign a cut from stock top down to stock bottom, adding tabs as desired:

2 Likes

Add toolpaths for the text and holes, then preview to verify, then make G-Code and cut.

Cutting in aluminum w/ a #122 we’ll need feeds and speeds. There is an example of this at:

These settings are:

  • Depth per Pass: 0.102mm
  • Stepover: 0.356mm
  • Spindle speed: 9200RPM
  • Feedrate: 190.068mm
  • Plungerate: 25.4mm

Managed to get it cut, but had to use Grbl’s feedrate override to finish the cut:

1 Like

Some Questions…

You said a technique to avoid “slotting.” What is slotting?

You added two offsets. Why two and what was the rational for the offset distances?

Thanks,

Allen

Slotting is cutting a slot just as wide as the endmill will cut — a follow path / Contour | No offset cut into the material — the tool is engaged along the entire leading edge of the cut (a half-circle).

The two offsets allowed one to cut a pocket which would leave a “roughing clearance” adjacent to the material. Then one can make a finishing pass to take off that last thickness of material to get to the final dimension.

Available at:

1 Like