# Spherical Jig/Mold for archtop guitar

From a topic on the Facebook Page

Eric Stein

My nephew is making a guitar and we have used my S4 for a few of the parts. He needs to very slightly bow the top of the body (I know that’s not true luthier terminology!). He would like to cut out a sphere segment to use as the “mold” to hold the top for gluing. Anyone here done something like that? First pic is a "depression/bowl) that’s a little hard to see. Ive done some google searches with limited success. Thanks

The dimensions of the board are 20mm x 760mm x 640 mm. The dished portion is on a 26 foot radius. My hope was to be able to do the other side on a 50 foot radius. Im not 100% sure there will be enough material left after the 26 foot radius is carved in to accommodate the 50, but it would sure make it a lot more convenient to have both on the same board.

OK. First we have to do a little math. Convert mm (green) to inch (blue), and feet (black) to inch.
Then determine how deep the depressions are, and how much material left in the center. (red)
I see a little bit of a flange in your picture, so I will use 750mm as my spherical section diameter.

Start a new CC file.

We make it a square so the entire circle is within the bounds of the workpiece. This is necessary to create the 3D shape. Otherwise it will try to round off from the flat edge that gets cut off.

Create a Circle 750mm in diameter (Type 375mm in the Radius field, and it will convert to inch)

Create a Rectangle your actual stock size (760mm x 640mm)

It doesn’t matter where you create them, we will align them next.

Select one of the shapes, Select Align Vectors Then select Align Vertical & Horizontal

Select the other vector & do the same thing.

Now to model the shapes. In the Modeling tab, select the rectangle, and Add Shape
Create a Flat, 0.787 Height component.

Now select the circle, and create a round, 0.344 Scale Height, and Subtract
When I hit apply in Build 757, it takes a while to calculate. Be patient & wait

Switch to the Toolpaths tab, and select Wood Grain for the material in the Simulation panel at the bottom. Switch back to the Model tab & Show 3D. You’ll have to rotate it around to get an idea of what it looks like.

Now let’s do a sanity check to make sure the shape is correct.
Back on the design tab, create any shape that has an edge going through the center point.
Go back into the Job Setup & change the height to 780mm (14.9606")
On the Model tab, select the new shape & create a component that is Flat, 0.443 height, and Equal Merge Type.

Now Show 3D, and look closely at the edge that crosses the center of the dish.

You can see in this area the “gauge block” that we created ‘washes out’ and shows no edge either raised or depressed. This indicates that our material is the right thickness in the center.

You can delete the last component in the Model tab, and the vector. And go back & change your stock height back to 760mm.

Save the file as something like: Arch_Top_Jig_26R.c2d
Now do a Save As… and name it Arch_Top_Jig_50R.c2d

You are now working in the 2nd (50R) part. So just delete the 2nd component (Subtract), and recreate it using 0.178 for the height to get the 50’ radius.

1 Like

OK, so let’s machine it with a 1/4" ball mill. I would go with the largest ball mill you can use in your machine. The larger the diameter, the better the finish, and the faster it will cut.
Note: You can use a 1/2" or 3/4" round router bit rather than an actual mill.

I’m going to want to limit the cut to the area inside both the circle & rectangle so I don’t waste time cutting any air.

Let’s use layers just to show one good use for them…

Select Edit → Show Layers, or just hit the “L” key
Select the Plus sign to add a new layer. I just name it “2”
Select the ellipsis (three dots) to the right of the layer, and select Activate, then hit OK

Now anything new we create will go on that layer.

Select the rectangle & circle and hit CTRL-D to duplicate them.
Click anywhere, then click Done.
Leave the new copies selected, and we’ll do a quick shortcut to center them.
Click Group Vectors
Click Align Vectors & select the Center bot vertical & horizontal option.
Now click Ungroup Vectors
Not big time saver when it’s only 2 vectors, but when it’s a bunch, or they are not centered about each other it will save some time.
Now hit L for layers again, and Hide the DEFAULT (Black) layer.

Select both vectors, and click the Boolean Intersection icon
This is the area we will cut within, so you can leave it selected

Go to the toolpaths tab & select 3D Rough
You can Use Current Selection, or Select by Layer & select layer 2
Change the tool to a 1/4" Ball Mill, and set the parameters to…

Stock to Leave: 0.0197 (0.5mm) is fine

With the vectors still selected, create a 3D finish path. It should default to the same tool as the previous operation. Change the stepover to 0.025, and the feedrate to 120

Show the simulation

Note the times. Just changing to a 1/2" tool and using larger stepovers cuts it down to

And a 3/4" tool…

Now, when setting it up on the machine, I used “Center” for my zero location because my workpiece is larger than the actual workpiece to get the model to create properly.
Just draw lines from adjacent corners on your stock to find the center. You should have room at the corners to clamp the workpiece without getting in the way of the toolpaths.

2 Likes

This topic was automatically closed after 30 days. New replies are no longer allowed.